Creo Parametric - Drawing Section Views - Full Aligned and Full Unfold

in creo parametric you can configure a wide variety of different section views in drawings in a previous video we took a look at full 1/2 local and full and local cross-sections in this video we'll take a look at the other 2d cross-sections for full aligned and full unfold let's start out with full aligned I'm gonna use this part over here so I will click on it and then use the open icon from the mini toolbar to open it up in its own separate window for the other options for section views you're going to use offset cross-sections you're going to use cross-sections that don't aren't defined by a single plane to do that let's go to the View tab over here from the section drop-down we can choose to create an offset cross-section and for the full aligned option on drawing views you're going to use non planar sections in the offset section let me show you what I mean by that in this particular part I want to create a section that goes vertical and then to the center over here and then down through the middle of this particular part and what will help me is if I create a datum axis and I know that I'm going to need an access later on for the drawing view so I might as well create one now so I will select this cylindrical surface and then from the mini toolbar I can choose to create a datum axis now I have it in there it is a underscore 26 let me turn on my axis display and there you can see it let's create our offset section I'll go to the section drop-down and then choose offset section this requires a sketch and I don't have one right now so I can define it inside of the cross section so I'm going to choose to sketch on this surface and then for the orientation I'm going to choose make sure that that this surface faces the top of the screen now I will click on the sketch button and it takes me in this guy mode let's go to our sketch orientation I have some sketch references automatically selected for me let's go to the references in here and I want to make sure that I get this a 26 axis in there so I can lock into it let's also grab this particular surface and just for safety I'm gonna grab this surface as well let's hit the solve button and then close out of here and my shape is going to be a bunch of lines so I can start off flying over here and then drag it up over here and you can dimension these if you want to I'm just gonna leave this at a big value or if you wanted to you could use delete segments and just trim it right to the model geometry if you want let's create another line it'll go from here and I'll let it snap to the midpoint of that is that what I want that should be it so that is good for that one now that I'm done I will hit the check marks get out of sketch mode and so there you see a preview of the section that we're getting if I want it to be on the other side I'll just use the flip button and this is the actual section that I want let's go to the hatching turn on the display of that and I'll go to properties let's change the name of this to section a and hit the check mark I like to edit my hatching right here in the model so let's right click on there and choose the edit hatch option usually I just make it denser so that you can see it then click the ok button so that is good for my cross-section let's now turn or deactivate it and turn off the display oops wrong one turn off the display of the hatching that's good we're back to the way that we were before let's use the window drop-down to get back to a drawing over here and before I create a new sheet for that particular part I'm going to add that model to the drawing that's generally the recommended practice for multi model drawings add the model first and then put in the sheet this is the number of that particular part let me select him and click the Open button and then done return out of the menu manager to create a new sheet you can use the new sheet icon there or you could use this button now we are on sheet number two let's create a new general view and I'm gonna use no combined State let's pick about over here to place it on the drawing sheet and let's see what the front view looks like do I want that one yep that one looks good over here let's go to the scale and she's a bigger scale something that you can see let's use a value of 0.5 and click the ok' button and that is good for that one let's change the sheet scale while we're at it and I don't need this note so I'll select it and then use the delete command and just gonna reposition it over here so here is my front view now I'm going to create a projection view of this one so let's click on it with the left mouse button and then use the projection view icon and create a projection view app over to the side over here so that is good for the projection view now I will double click on it and go to the sections command let's put in a 2d cross-section I'll hit the plus sign and there's our section a this time I'm just gonna leave it as a full section and click the apply button and so that way you can see what it looks like over here the reason I'm doing this is so that I can contrast it with the full aligned option as well let's move everything over running out a sheet a little bit someone get the other view same projection view over here so let's select view and then projection and position it right about over here next to the other one and then double-click on it now we can go to sections over here I'm gonna do a 2d section again and I'll hit the plus sign select section a but instead of full you have the option to do half one side or the other side of a datum plane local but now we have the option over here for full aligned and I'll select that one and it asked me for a reference axis and I'm gonna use the model tree to select the axis that I created in the part and we can hit the apply button and so you'll notice that it's again it's sort of like unfolds it about that axis over there so you'll notice that it's longer than the view over to the right and let's click in the arrow display field and select this view and then hit the apply button that way we get our cutting errors for the a section in there and so I always warn people be very careful when you're using the full aligned or full unfolded options because they can actually confuse people in terms of the net result in there so there we have the full aligned let's take a look at doing the full unfolded option and I'll go to a different part over here and I'm gonna create another offset cross section and it's going to consist of a bunch of planar sections the one that I did before fold it for the full aligned it was a couple of lines at an angle to each other so let's go about doing this and I'm gonna create an offset cross section that slices through this feature over here goes down the middle and then slices through this one over there so let's go to the View tab and then section offset section again we need a sketch let's hit the define button I'm gonna sketch on surface and let's choose this surface to face the top of the screen I'll click the sketch button let's go to actually before we go to our sketch orientation I'm gonna add in a bunch of sketch references let me grab the this yeah well I'll grab that edge let's grab this cylindrical surface there I really want the cylindrical surface over there and let's see I also want to slice through this one over here let me turn on my axis display let me go to my layers unhide my axis layers now we got now I've got better references that I want to use so let's grab this axis over here as a reference and grab this axis as a reference let me get rid of that edge as one of my references alright so that is good let's click the solve button let's go to our sketch view and in this particular case I am just going to use a bunch of lines that extend beyond the part oops looks like I am this particular reference is not going through these different holes let's do that as well let's go back to the references and let's see I'm guessing that one I don't want let's now add in this particular axis as a reference and to help me sketch I'm just going to throw in a vertical centerline then whatever I need to do in order to make what I want and I don't think I need to see my axis anymore so now let's do our three lines let's do a line from here to there and then up through here and then add our there so that is good again I'm not gonna change the dimensions let's right-click and then choose the checkmark to get out of sketch mode and it shows us the side or the part that it's keeping and I could flip it if I wanted to retain the other side and I decide that you know what this is actually what I want to keep let me go down to the bottom of the model tree I don't have any sections let's go to here and choose a call this section a let's turn on the display of hatching and hit the check mark let me go to the section and I'm not happy with the hatching so once again I will right-click on the cross-section use the Edit hatching and let's get lines but quite a bit denser inside of there and click the ok' button so that is good in here let me go back to the model tab I want to see if I have a view set up for my front view and I do not let's deactivate the cross-section and turn off the display of the hatching and let's see for my first view that I want to use I'm going to set up let's have a front view sort of like this so I will choose to go to the saved views list so I actually do have a view called front yep that is good I will use that for my first view on the drawing let's go back to my drawing and I'm going to once again add another drawing model add model and let me go to oops my working directory is left the valve cover so now that is the active part we can hit done return out of the menu manager I'll use the new sheet icon this time now let's create our first view I will hold down the right mouse button and choose general view and I'll use no combining States let's left-click to place the first there this one is going to be a front view let me change the scale let's use now let's use a scale of 0.5 and hit the ok' button let me create a couple of projection views a projection view to the top and a projection view to the side let's grab this over here and drag it down and grab this one and drag it down now let's see for the view that I want to display the section in I want to display it and let's see let's start off with actually might be the front view that I want the es section to appear in let's try doing it in there I will double click on the view let's go to the sections category - the cross section and I'll hit the plus sign and yep this one so this is one that is appropriate for the cross section right now I'm using the full option and I will click the apply button and ok and you can see how the cross section looks if I right click on this view I can choose add arrows let's put the arrows in the top view and so that way you can see how it cut through the model over here let's actually get rid of this view I'll select it and hit delete I'm gonna create another front view but this time I'm going to use a full unfolded cross section we can see the comparison between the two views so I will right click general view no combined State let's place it right about over here let's use the saved view called front I'll hit the apply button and for the scale let's change it so that's using the same scale as the other view 0.5 and here I'll actually use the alignment commando yes I want to apply the changes I almost never used the alignment option but since they're the same view let's align these two views together and hit the apply button that way it's just that the are even with each other so here you see the front view I'm gonna click OK out of here so we've got section a a displayed in this particular view but it's just a full section let's take a look at what happens when we use the full unfold option I'll double click on the view let's go to sections and do a 2d section again I'll hit the plus sign and choose a and I'll hit the apply button first so right now these two views look the same if I go to the drop down we have the option to do half local and here's the one that we haven't used before the full unfold option I'll select it and hit the apply button and whoa now the view looks much different than the previous ones let me click OK out of here and turn off my datum plane door repaint so that will you get the datum plane display and now you'll notice that it goes through the section here it shows let's see it goes through here and then follows along the definition of the sketch and then through over here and so even though these were both front views and they're using sections this is a full and this is a full unfold and looks like this one even got turned upside down so again there's a big difference when you're using the full aligned and full unfold options for those offset cross sections with planar and non planar sketches I hope you enjoyed this video for more information please visit WWE windchill comm if you learn something from this video please give it a thumbs up and if you like this video please click the subscribe button to be informed when new videos are uploaded thank you very much

Channel: Creo Parametric

Views: 5,533

Keywords: creo parametric, ptc creo, creo ptc, creo parametric tutorial, creo parametric 2.0, creo parametric 2.0 tutorial, creo parametric 3.0, creo parametric 3.0 tutorial, creo parametric 4.0, creo parametric 4.0 tutorial, creo parametric 5.0, creo parametric 5.0 tutorial, creo parametric 6.0, creo parametric 6.0 tutorial, drawings in creo, creo parametric drawings, creo parametric sections, creo parametric section views, creo full aligned, creo full unfold

Id: otg4SX894iQ

Length: 17min 17sec (1037 seconds)

Published: Mon Apr 27 2020